iLogic Update and Zoom All after a size change.

Here is a quick tip that you might find helpful.

Issue:
You have some iLogic code in a rule that changes the length of a part. It works great but you'd like to have the rule update the part on screen and zoom to fit, so that a large change of length will fit on screen.
 
Solution:
You can add the following lines of code to your rule to make this happen:

'update all
iLogicVb.UpdateWhenDone = True
'zoom all
ThisApplication.ActiveView.Fit

Autodesk iLogic: Highlight and Update Features During Changes

Issue:

You have some iLogic code that prompts the user for a number of different inputs. But currently the features only update once the entire rule is run. You'd like for the features to update as the user steps through the input, so they have visual input as to what they've changed. And if each feature could be highlighted as it is selected by the iLogic code, so that the user knows which feature is being changed, that would be the cat's meow!

Solution:

To pull this off you need to use the following two lines after each input is gathered:

'If your rule has changed any parameter values, this will apply the new values to the Inventor model. If you don't use this, the values are not applied until the rule has finished running.

RuleParametersOutput()

'If this is included in a rule,  iLogic will do an update for the document. This update is the same as the Update button in the user interface.

iLogicVb.UpdateWhenDone = True

To highlight the feature, simply change its color before the inputbox is issued, and then change it back immediately afterward. See the example code below.

Here is the example code:

'Start of iLogic Code--------------------------------------------------

'used to trigger rule for testing or running the rule

Trigger = iTrigger0

'ignores errors and continues on with the code

On Error Resume Next

'set the feature color to red and then prompts the user for input

'then pushes the parameter change to the part and updates before moving on

Feature.Color("Hole1") = "Red"

Dia1= InputBox("Enter Diameter of " & "Hole1", "iLogic Hole Diameter", Dia1)

Feature.Color("Hole1") = "As Part"

RuleParametersOutput()

iLogicVb.UpdateWhenDone = True

'set the feature color to red and then prompts the user for input

'then pushes the parameter change to the part and updates before moving on

Feature.Color("Hole2") = "Red"

Dia2= InputBox("Enter Diameter of " & "Hole2", "iLogic Hole Diameter", Dia2)

Feature.Color("Hole2") = "As Part"

RuleParametersOutput()

iLogicVb.UpdateWhenDone = True

'set the feature color to red and then prompts the user for input

'then pushes the parameter change to the part and updates before moving on

Feature.Color("Hole3") = "Red"

Dia3= InputBox("Enter Diameter of " & "Hole3", "iLogic Hole Diameter", Dia3)

Feature.Color("Hole3") = "As Part"

RuleParametersOutput()

iLogicVb.UpdateWhenDone = True

'set the feature color to red and then prompts the user for input

'then pushes the parameter change to the part and updates before moving on

Feature.Color("Hole4") = "Red"

Dia4= InputBox("Enter Diameter of " & "Hole4", "iLogic Hole Diameter", Dia4)

Feature.Color("Hole4") = "As Part"

RuleParametersOutput()

iLogicVb.UpdateWhenDone = True

'prompts the user for input

'then pushes the parameter change to the part and updates before moving on

Length= InputBox("Enter Length", "iLogic Length", Length)

RuleParametersOutput()

iLogicVb.UpdateWhenDone = True

'zoom all

ThisApplication.ActiveView.Fit

'End of iLogic Code--------------------------------------------------


Look for more iLogic examples on this blog or in the chapter dedicated to iLogic Basics in the next edition of Mastering Autodesk Inventor book (due out in June of 2011 if all goes well).